Defines advanced edge display options for drawing views. The Advanced Edge Display Options dialog box is available using the Advanced button on the first page of the Drawing View Creation Wizard.

You can override these options for individual views on the Advanced page (Drawing View Properties dialog box).

Limit Edge Creation

Only generate edges inside and overlapping cropped boundaries

Minimizes VHL drawing view processing time by limiting edge creation for any cropped views or independent detail views. When this check box is selected, only edges completely inside or overlapping the view cropping boundary are generated. When this check box is cleared, all edges inside, outside, and overlapping the view cropping boundary are generated.

Note:

Geometry created with the Draw In View command is not affected by this setting.

Show edges created by cutting plane line vertices

When you create a section view using a cutting plane that is defined by multiple line segments, you can use this option to show or hide the resulting edges in a drawing view.

When this option is cleared, edges created by cutting plane line vertices are hidden when the drawing view is created. When this option is set, these edges are visible. The default setting is cleared.

This option applies to 2D section and revolved section views. It does not apply to 2D broken-out section views. The default setting is cleared.

Note:

Not all edge cases are handled by this processing rule. For those edges that are not, you can use the Hide Edges command to hide them.

Simplify B-spline Edges

Always

B-spline geometry from part edges is always converted to simple geometry.

Only edges outside of the plane of the drawing view

Only B-spline geometry from part edges non-parallel to the plane of the drawing view are converted to simple geometry.  This is the default for newly placed views.

Never

B-spline geometry from part edges is never converted to simple geometry.

Part Intersections

Processing part intersections can yield better drawing view results in cases such as press fits, where parts slightly intersect.

Do not process intersections

Specifies that part intersections are not processed.  This is the fastest option, and the default for newly placed views.

Process intersections

Without creating face intersections (fast)

Creates part edges within the intersections of overlapping bodies.  The edges formed between intersecting faces of overlapping bodies are not created.

Create face intersections of threaded parts (slow)

Creates face intersections of overlapping bodies for threaded parts on which outer diameter and inner diameter threads overlap.

Create all face intersections (slowest)

Creates face intersections for all overlapping bodies.  This is the slowest option.