Draft Options
Displays the Draft Options dialog box so you can set draft construction options.
Main Steps
Draft Plane
Defines the plane that the draft angle is measured against. The normal vector of the selected plane defines the draft zero angle.
Select Parting Geometry
Specifies the parting geometry you want to use for drafts that are defined by a parting line, parting surface, or part edge. This step is not available when you use the From Plane option on the Draft Options dialog box.
Select Face
Defines the faces to which you want to add draft.
Draft Direction
Defines the side toward which you want to apply the draft angle. When this step is active, a dynamic line swings from one side of the draft plane to the other as you move your cursor. Position the cursor so that the line is on the side where you want to apply the draft, then click.
Finish/Cancel
This button changes function as you move through the feature construction process. The Finish button constructs the feature using input provided in the other steps. Once you construct the feature, you can edit it by re-selecting the appropriate step on the command bar. The Cancel button discards any input and exits the command.
Draft Plane Options
Create-From Options
Sets the method of defining the profile plane or specifies that you want to construct the feature using an existing sketch. Depending on the model you are constructing, some of the options listed may not be available.
Coincident Plane—Specifies that you want to define a plane that is coincident to an existing reference plane or a planar face on the part. When you set this option, a default X-axis and direction is applied to the new reference plane. You can use keyboard accelerators to define a different X-axis and direction for the new reference plane.
Parallel Plane—Specifies that you want to define a plane that is parallel to an existing reference plane or a planar face on the part. When you set this option, you can specify the parallel offset distance. When you set this option, a default X-axis and direction is applied to the new reference plane. You can use keyboard accelerators to define a different X-axis and direction for the new reference plane.
Angled Plane—Specifies that you want to define a plane that is at an angle to an existing reference plane or planar face on the part. When you set this option, you can specify the angle value you want.
Perpendicular Plane—Specifies that you want to define a plane that is perpendicular to an existing reference plane or planar face on the part.
Coincident Plane By Axis—Specifies that you want to define a plane that is coincident to an existing reference plane or a planar face on the part. When you set this option, you define the X-axis and direction for the new reference plane using a linear edge, a planar face, or another reference plane.
Plane Normal to Curve—Specifies that you want to define a plane that is perpendicular to a curve you select. This is the default option when constructing a helix using the Perpendicular option.
Plane By 3 Points—Specifies that you want to define a plane by three keypoints you select.
Feature's Plane—Specifies that you want to define a plane that is coincident to a reference plane used to define an earlier feature. You can select the feature you want using Feature PathFinder or in the graphic window. This option is not available when constructing the base feature.
Last Plane—Automatically selects the reference plane used for the previous feature. This option is not available if the last feature was a pattern or when constructing the base feature.
Tangent Plane—Specifies that you want to define a plane that is tangent to a curved face on the part. You can select a cylinder, cone, sphere, torus, or b-spline surface. When you set this option, you can also specify the angular rotation value. When you set this option, a default X-axis and direction is applied to the new reference plane. You can use keyboard accelerators to define a different X-axis and direction for the new reference plane.
Select Options
Select
Sets the method of selecting faces to draft and parting geometry to define the draft. You can use any combination of selection methods to select geometry.
Selecting part edges and parting lines:
Edge—Allows you to select individual part edges.
Chain—Allows you to select tangentially continuous chains of faces.
Selecting a parting surface:
Face—Allows you to select part faces.
Selecting faces to draft:
Face—Allows you to select part faces.
Chain—Allows you to select tangentially continuous chains of faces.
Loop—Allows you to select all the faces adjacent to a selected surface loop. First select a face, then select individual loops of that face. When you locate a loop, all surfaces adjacent to the loop highlight.
All Normal Faces—Allows you to quickly select all part faces that are normal to the draft plane. If you want to select a large number of normal faces, but not all of them, start with this option and then re-set the selection method to Face to de-select the faces you do not want to draft.
Deselect (x)
Clears the selection.
Accept (check mark)
Accepts the selection.
Draft Angle
Sets the draft angle you want. The draft angle is measured from the normal vector of the plane you specified in the Draft Plane step.
Other command bar Options
Name
Displays the feature name. Feature names are assigned automatically. You can edit the name by typing a new name in the box on the command bar or by selecting the feature and using the Rename command on the shortcut menu.