When you migrate any SolidWorks part file the material definition is extracted. This material is assigned to the Solid Edge document if the material name exists in the Solid Edge Material.mtl file. To ensure that the SolidWorks material name exists in the Solid Edge Material file, Solid Edge provides a tool to convert the SolidWorks.sldmat file to the Solid Edge Material.mtl file.

The SWmat2SEMat.exe utility is delivered as part of the Server side application but it must be run from the Solid Edge program folder.

Before running the utility, there are a few things to consider:

• You should make a copy of the Solid Edge Material.mtl file before running the utility.

• If the SolidWorks data migration application is on a different machine than the Solid Edge application you must make a copy of the SolidWorks.sldmat and place it on the Solid Edge machine.

• After successfully converting the material table ensure that the Solid Edge\Options\File location pointer is pointing to the appropriate file.

• Before starting a migration ensure that SolidWorks is pointing to the same material database folder that was previously converted.

1. From the server side application, copy Solid Edge Data Migration\Component\Program\SWmat2SEMat.exe to the Solid Edge Program folder.

2. Open a DOS window.

3. CD to the Solid Edge Program folder.

4. Run SWmat2SEMat.exe and set the following:

   • Argument 1: Full path and name of the SolidWorks materials.sldmat (in double quotes).

     Example:

     "C:\Program Files\SolidWorks Corp\SolidWorks\lang\english\sldmaterials\solidworks materials.sldmat"

   • Argument 2: Full path and name of the Solid Edge Material.mtl file (in double quotes).

     Example:

     "C:\Program Files\Solid Edge ST6\Preferences\Material.mtl"

As part of the material conversion, Solid Edge also imports and applies the SolidWorks texture map file associated with the material definition.

This texture map file is optional and to use the file in Solid Edge you need to:

1. Create a SW_textures folder in SE installation path\images\textures.

   Example:

   ""C:\Program Files\Solid Edge ST6\Images\textures\SW_textues""

2. Copy any SolidWorks texture map files to this folder.

When you migrate any SolidWorks part file the hole definitions including thread attributes are migrated.

Solid Edge provides a tool as part of the SolidWorks data migration (server side application) software. This tool converts the SolidWorks hole database (SWBrowser.mdb to a Solid Edge Holes, and pipes.txt files.

1. Open a DOS window.

2. CD to the Solid Edge Program folder.

3. Run SEHolePipeTxtFromSW.exe and set the following:

   • Argument 1: Holes or Pipes (first argument is .txt file containing the hole or pipe information always the first argument.

   • Argument 2: Path and name of the SWBrowser.mdb to be converted (in double quotes).

     Example:

     "C:\Program Files\SolidWorks Corp\SolidWorks\Toolbox\data utilities\lang\English\swbrowser.mdb"

   • Argument 3: Path and name of the Solid Edge text file to be created (must be a unique name for the creation of the file).

   • Argument 4: Units standards such a AI, DIN, and ISO within the SWBrowser.mdb file to be converted).

     The following standards are available:

     Standard	Input to the conversion utility
     ANSI Inch	ai
     AMSI Metric	am
     BSI	bsi
     DIN	din
     GB	gb
     IS	is
     ISO	iso
     JIS	jis
     KIS	ks
     MIL	mil

The SolidWorks data migration software supports the following Solid Edge assembly relationships.

SolidWorks	Solid Edge	Comments
Coincident, including Distance Face Normals opposite of each other	Planar Align, including offset	Only face based alignment is supported. Alignments other than face based are placed as floating including: Base Reference Plane, User Defined Reference Plane, and Edge Based, Sketch, Vertex, and Coordinate System.
Coincident, including Distance Face Normals in the same direction	Planar Mate, including offset	Only face based mates are supported. Alignments other than face based are placed as floating including: Base Reference Plane, User Defined Reference Plane, and Edge Based, Sketch, Vertex, and Coordinate System.
Concentric	Axial Align	The Axial Align Constrain is always applied with Unlocked Rotation option. Only surface based element types are supported: Cylinder, Cone, Torus, Sphere, and Spun Surface. Concentric relationships other than face based are placed as floating including: Edge, Sketches, Points, and Coordinate Systems.
Fixed	Grounded or Fixed	All SolidWorks part components with a fixed property or relationship are grounded in Solid Edge.

You can use the Get all Configuration Members parameter in the SolidWorks2SE.ini file to control how assembly configurations are applied as family of assemblies during migration.

The default value for the parameter is 0. When the parameter is set to 0 the migration includes the active configuration for the top level assembly, including all parts and assemblies that are referenced by the configuration. In other words, you get what you see. For each assembly, including the top assembly, with multiple configurations, the configuration name is appended to the file name.

For suppressed parts without a configuration, a Solid Edge part is created with the part occurrence properties set as follows:

• Reference = Yes

• Assembly reports = No

• Display in higher level = No

• Physical Properties = No

• Selectable = No

• Check Interference = No

When the parameter is set to 1 all SolidWorks assembly configurations are migrated as a Solid Edge family of assemblies.

For SolidWorks family of assemblies configuration names that exceed 31 characters:

• The name is truncated to the first 28 characters.

• A value of 0 - 999 is appended to the truncated configuration to keep it unique.

• A property is added to the family of assemblies member as a local custom property to provide the user with a history of the change.

Alternate position assemblies are migrated to Solid Edge as a family of assemblies member.

With suppressed configurations or simplifies assemblies, for each suppressed part in the SolidWorks configuration the part is added as an excluded occurrence in a Solid Edge family of assemblies. Suppressed parts in SolidWorks can be optionally added to the bill of materials. However, Solid Edge does not support this concept so the excluded occurrence is not added to the Solid Edge bill of materials.

Relationship suppression is only available for mates, aligns, and axial aligns, including static distance values. If the Create Assembly Constraints on Migration is set to 0, relationship suppression is not available because all parts are grounded. Suppressed relationships that are not included in the SolidWorks configuration, or in an assembly with a single configuration, are imported and suppressed in Solid Edge.

In family of assemblies with different part configurations, for each SolidWorks family of parts all members of the family of parts is created and saved to disk. Part configuration names are appended to the part file name when the part file contains more than one configuration.

Adjustable assemblies are not supported. Speed pack configurations are not migrated. Display states are not translated and all parts are shown when migrated to Solid Edge.

You can use the Create Hole Features on Migration parameter in the SolidWorks2SE.ini file to control how Solid Edge hole features are created during migration.

The default value for the parameter is 1. When the parameter is set to 1 hole features, including thread attributes, are created during the migration. Hole features are only applied to synchronous bodies. No hole feature is created when the migration is targeted for the ordered environment.

When the parameter is set to 0 no hole or thread attributes are captured or applied during migration.

• Translate SolidWorks documents to Solid Edge

• Data migration Configuration

• Opening foreign files in Solid Edge